All Frameworks Class Hierarchy This Framework Indexes Previous Next

CATGSMUseItf Interface CATIGSMUseLoft

Usage: an implementation of this interface is supplied and you must use it as is. You should not reimplement it.

interface CATIGSMUseLoft

Interface to loft surface feature.
Role: Allows you to access data of the Loft feature.

LICENSING INFORMATION: Creation of volume result requires GSO License
if GSO License is not granted , settting of Volume context has not effect

See also:

Method Index

o AddGuide(CATIMmiMechanicalFeature_var,CATGSMLoftAddType,CATIMmiMechanicalFeature_var): Adds guide to the lofted surface.
o AddSection(CATIMmiMechanicalFeature_var,CATGSMLoftAddType,CATIMmiMechanicalFeature_var): Adds section to the lofted surface.
o AddSection(CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var&,CATIMmiMechanicalFeature_var&,CATGSMClosingPointCreationDiag&,CATGSMLoftAddType,CATIMmiMechanicalFeature_var): Adds section to the lofted surface.
o GetAllGuides(CATLISTV(CATIMmiMechanicalFeature_var)&): Gets informations about the guides of the lofted surface.
o GetAllGuides(CATLISTV(CATIMmiMechanicalFeature_var)&,CATLISTV(CATIMmiMechanicalFeature_var)&)
o GetAllGuidesAndSupports(CATLISTV(CATIMmiMechanicalFeature_var)&,CATLISTV(CATIMmiMechanicalFeature_var)&,CATListOfInt&): Gets informations about the guides of the lofted surface.
o GetAllSections(CATLISTV(CATIMmiMechanicalFeature_var)&,CATListOfInt&,CATLISTV(CATIMmiMechanicalFeature_var)&,CATIMmiMechanicalFeature_var&,CATIMmiMechanicalFeature_var&)
o GetAllSectionsAndSupports(CATLISTV(CATIMmiMechanicalFeature_var)&,CATListOfInt&,CATLISTV(CATIMmiMechanicalFeature_var)&,CATIMmiMechanicalFeature_var&,enum CATGSMContinuity&,CATIMmiMechanicalFeature_var&,enum CATGSMContinuity&): Gets informations about the sections of the lofted surface.
o GetAreaLaw(CATICkeLaw_var&): Gets the optional area law for multi-sections element definition.
o GetAreaLawTolerance(double&): Gets the tolerance applied to area law.
o GetAreaLawTolerance(CATICkeParm_var&): Gets the tolerance applied to area law.
o GetBooleanOperation(int&): Gets boolean operation for closed lofted surface.
o GetCanonicalDetection(CATGSMCanonicalSurfaceDetection&): Gets information about detection of canonical surfaces of the output surface.
o GetCompSectionTangent(CATGSMComputedTangentType&,CATGSMComputedTangentType&): Gets if the tangent is a computed tangent surface to the start section or end section from the lofted surface.
o GetContext(CATGSMFeatureContextType&): Gets context type for existing feature.
o GetFacesForClosing(CATIMmiMechanicalFeature_var&,CATIMmiMechanicalFeature_var&): Gets if the support is a computed support surface to the start section or end section from the lofted surface.
o GetRelimitation(int&): Gets informations about relimitation of the lofted surface.
o GetSectionCoupling(int&): Gets informations about the coupling between section of the lofted surface.
o GetSmoothAngleThreshold(double&): Gets angular threshold value (angle) allowed during lofting operation in order to smooth it.
o GetSmoothAngleThreshold(CATICkeParm_var&): Gets angular threshold value (angle) allowed during lofting operation in order to smooth it.
o GetSmoothAngleThresholdActivity(CATBoolean&): Gets information whether a angular threshold is allowed or not during lofting operation in order to smooth it.
o GetSmoothDeviation(double&): Gets deviation value (length) allowed during lofting operation in order to smooth it.
o GetSmoothDeviation(CATICkeParm_var&): Gets deviation value (length) allowed during lofting operation in order to smooth it.
o GetSmoothDeviationActivity(CATBoolean&): Gets information whether a deviation is allowed or not during lofting operation in order to smooth it.
o GetSpine(int&,CATIMmiMechanicalFeature_var&): Gets the spine of the lofted surface.
o ModifyGuideCurve(CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var): Modifies the curve of a guide from the lofted surface.
o ModifySectionCurve(CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var): Modifies the curve of section from the lofted surface.
o ModifySectionCurve(CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var&,CATIMmiMechanicalFeature_var&,CATGSMClosingPointCreationDiag&): Modifies the curve of section from the lofted surface.
o ModifySectionOrient(CATIMmiMechanicalFeature_var,CATGSMOrientation): Modifies the orientation of the curve of a section from the lofted surface.
o RemoveFaceForClosing(CATIMmiMechanicalFeature_var): Removes face used to close the lofted surface.
o RemoveGuide(CATIMmiMechanicalFeature_var): Removes guide from the lofted surface.
o RemoveGuideSupport(CATIMmiMechanicalFeature_var&): Removes a support surface of a guide from the lofted surface.
o RemoveGuideTangent(CATIMmiMechanicalFeature_var)
o RemoveSection(CATIMmiMechanicalFeature_var): Removes section from the lofted surface.
o RemoveSectionPoint(CATIMmiMechanicalFeature_var): Removes a closing point of a section from the lofted surface.
o RemoveSectionSupport(CATIMmiMechanicalFeature_var&): Removes a support surface of a section from the lofted surface.
o RemoveSectionTangent(CATIMmiMechanicalFeature_var)
o SetAreaLaw(CATICkeLaw_var&): Sets the optional area law for multi-sections element definition.
o SetAreaLawTolerance(double): Sets the tolerance applied to area law, if specified.
o SetBooleanOperation(CATGSMLoftBooleanOp): Sets boolean operation for closed lofted surface.
o SetCanonicalDetection(CATGSMCanonicalSurfaceDetection): Sets information about detection of canonical surfaces of the output surface.
o SetCompSectionTangent(CATIMmiMechanicalFeature_var,CATGSMComputedTangentType): Sets a computed tangent surface to the start section or end section.
o SetContext(CATGSMFeatureContextType): Sets context type to generate a Surface or Volume.
o SetFaceForClosing(CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var): Sets face for closing the lofted surface.
o SetGuideSupport(CATIMmiMechanicalFeature_var&,CATIMmiMechanicalFeature_var&,enum CATGSMContinuity&): Sets a support surface to a guide from the lofted surface.
o SetGuideTangent(CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var)
o SetRelimitation(CATGSMLoftRelimitationType): Sets informations about relimitation of the lofted surface.
o SetSectionCoupling(CATGSMCouplingType): Sets informations about the coupling between section of the lofted surface.
o SetSectionPoint(CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var): Sets a closing point to a section from the lofted surface.
o SetSectionSupport(CATIMmiMechanicalFeature_var&,CATIMmiMechanicalFeature_var&,enum CATGSMContinuity&): Sets a support surface to a section from the lofted surface.
o SetSectionTangent(CATIMmiMechanicalFeature_var,CATIMmiMechanicalFeature_var)
o SetSmoothAngleThreshold(double): Sets angular threshold value (angle) allowed during lofting operation in order to smooth it.
o SetSmoothAngleThreshold(CATICkeParm_var&): Sets angular threshold value (angle) allowed during lofting operation in order to smooth it.
o SetSmoothAngleThresholdActivity(CATBoolean): Sets information whether a angular threshold is allowed or not during lofting operation in order to smooth it.
o SetSmoothDeviation(double): Sets deviation value (length) allowed during lofting operation in order to smooth it.
o SetSmoothDeviation(CATICkeParm_var&): Sets deviation value (length) allowed during lofting operation in order to smooth it.
o SetSmoothDeviationActivity(CATBoolean): Sets information whether a deviation is allowed or not during lofting operation in order to smooth it.
o SetSpine(CATGSMLoftSpineType,CATIMmiMechanicalFeature_var): Sets the spine to the lofted surface.

Methods

o AddGuide

public virtual AddGuide(	const	`iGuide`,
	const	`iAddType`	`= CATGSMLoftAdd` ,
	const	`iGuideRef`	`= NULL_var` )

Adds guide to the lofted surface.

Parameters:

iGuide: guide curve to be added
iAddType: type of adding : CATGSMLoftAdd, iSection will be added at the end of the guide list. CATGSMLoftAddAfter, iGuide will be added after iGuideRef. CATGSMLoftAddBefore, iGuide will be added before iGuideRef.

See also:

iGuideRef

guide curve used as a reference for CATGSMLoftAddAfter and CATGSMLoftAddBefore adding type

o AddSection

public virtual AddSection(	const	`iSection`,
	const	`iAddType`	`= CATGSMLoftAdd` ,
	const	`iSectionRef`	`= NULL_var` )

Adds section to the lofted surface.

Parameters:

iSection: section curve to be added
iAddType: type of adding : CATGSMLoftAdd, iSection will be added at the end of the section list. CATGSMLoftAddAfter, iSection will be added after iSectionRef. CATGSMLoftAddBefore, iSection will be added before iSectionRef.

See also:

iSectionRef

section curve used as a reference for CATGSMLoftAddAfter and CATGSMLoftAddBefore adding type

o AddSection

public virtual AddSection(	const	`iSection`,
		`oCurveSection`,
		`oClosingPoint`,
		`oPtDiag`,
	const	`iAddType`	`= CATGSMLoftAdd` ,
	const	`iSectionRef`	`= NULL_var` )

Adds section to the lofted surface.

Parameters:

iSection: section to be added : curve or face.
oCurveSection: if iSection is a face, oCurveSection is the boundary of the face. oCurveSection is used as section curve. if Part design, the face is used to close the Loft.
oClosingPoint: if iSection is a closed curve, oClosingPoint is a new closing point of iSection. if iSection is a face, oClosingPoint is a new closing point the boundary of iSection.
oPtDiag: Closing Point diagnosis.

See also:

iAddType

type of adding : CATGSMLoftAdd, iSection will be added at the end of the section list. CATGSMLoftAddAfter, iSection will be added after iSectionRef. CATGSMLoftAddBefore, iSection will be added before iSectionRef.

See also:

iSectionRef

section curve used as a reference for CATGSMLoftAddAfter and CATGSMLoftAddBefore adding type

o GetAllGuides

public virtual GetAllGuides( oGuides)

Gets informations about the guides of the lofted surface.

Parameters:

oGuides: list of the guides curves.

o GetAllGuides

public virtual GetAllGuides(		`oGuides`,
		`oGuideSupports`)

Deprecated:

V6R2013x CATIGSMUseLoft#GetAllGuidesAndSupports Gets informations about the guides of the lofted surface.

Parameters:

oGuides: list of the guides curves.
oGuideSupports: list of the supports corresponding to the guides curves.

o GetAllGuidesAndSupports

public virtual GetAllGuidesAndSupports(		`oGuides`,
		`oGuideSupports`,
		`oContinuities`)

Gets informations about the guides of the lofted surface.

Parameters:

oGuides: list of the guides curves.
oGuideSupports: list of the supports corresponding to the guides curves.
oContinuities: list of the contintuities of the guide curves with the supports (0 means no continuity, 1 means CATGSMContinuity_Tangency and 2 means CATGSMContinuity_Curvature).

o GetAllSections

public virtual GetAllSections(		`oSections`,
		`oOrientation`,
		`oPoint`,
		`oStartSectionSupport`,
		`oEndSectionSupport`)

Deprecated:

V6R2013x CATIGSMUseLoft#GetAllSectionsAndSupports Gets informations about the sections of the lofted surface.

Parameters:

oSections: list of the section curves.
oOrientation: list of the orientations of the section curves.
oPoint: list of the closing points corresponding to the section curves.
oStartSectionSupport: support surface at start section.
oEndSectionSupport: support surface at end section.

o GetAllSectionsAndSupports

public virtual GetAllSectionsAndSupports(		`oSections`,
		`oOrientation`,
		`oPoint`,
		`oStartSectionSupport`,
		`oStartContinuity`,
		`oEndSectionSupport`,
		`oEndContinuity`)

Gets informations about the sections of the lofted surface.

Parameters:

oSections: list of the section curves.
oOrientation: list of the orientations of the section curves.
oPoint: list of the closing points corresponding to the section curves.
oStartSectionSupport: support surface at start section.
oEndSectionSupport: support surface at end section.

o GetAreaLaw

public virtual GetAreaLaw( oLaw)

Gets the optional area law for multi-sections element definition. The output law is a length law.

Parameters:

oLaw: Specified length law for area definition

See also:

o GetAreaLawTolerance

public virtual GetAreaLawTolerance( oLawTolerance)

Gets the tolerance applied to area law.

Parameters:

oLaw: Specified area law tolerance value in mm

See also:

o GetAreaLawTolerance

public virtual GetAreaLawTolerance( oLawTolerance)

Gets the tolerance applied to area law.

Parameters:

oLaw: Specified area law tolerance parameter

See also:

o GetBooleanOperation

public virtual GetBooleanOperation( oOperation)

Gets boolean operation for closed lofted surface. TO BE USED ONLY for Part Loft (closed loft)

Parameters:

oOperation: type of operation.

See also:

o GetCanonicalDetection

public virtual GetCanonicalDetection( oDetection)

Gets information about detection of canonical surfaces of the output surface.

Parameters:

oDetection: if canonical surfaces are detected and converted into plane or not and how; possible values are CATGSMNoDetection, CATGSMPlaneOnlyDetection and CATGSMCanonicalDetection.

See also:

o GetCompSectionTangent

public virtual GetCompSectionTangent(		`oStartCompSectionTangent`,
		`oEndCompSectionTangent`)

Gets if the tangent is a computed tangent surface to the start section or end section from the lofted surface. The section must have been set as a face.

Parameters:

oStartCompSectionTangent: start section tangent is computed or not,

See also:

oEndCompSectionTangent

end section tangent is computed or not,

See also:

o GetContext

public virtual GetContext( oContextType)

Gets context type for existing feature.

Parameters:

oContextType: CATGSMSurfaceCtxt if the result is surface, CATGSMVolumeCtxt if it is volume

See also:

o GetFacesForClosing

public virtual GetFacesForClosing(		`oStartFace`,
		`oEndFace`)

Gets if the support is a computed support surface to the start section or end section from the lofted surface. The section must have been set as a face.

Parameters:

oStartFace: start face used to close the loft. NULL_var, if there is no start face.
oEndFace: end face used to close the loft. NULL_var, if there is no end face.

o GetRelimitation

public virtual GetRelimitation( oRelimitation)

Gets informations about relimitation of the lofted surface.

Parameters:

oRelimitation: type of relimitation.

See also:

o GetSectionCoupling

public virtual GetSectionCoupling( oCoupling)

Gets informations about the coupling between section of the lofted surface.

Parameters:

oCoupling: type of coupling between section.

See also:

o GetSmoothAngleThreshold

public virtual GetSmoothAngleThreshold( oSmoothAngleThreshold)

Gets angular threshold value (angle) allowed during lofting operation in order to smooth it.

Parameters:

oSmoothAngleThreshold: Numerical value.

o GetSmoothAngleThreshold

public virtual GetSmoothAngleThreshold( ohSmoothAngleThresholdCkeParm)

Gets angular threshold value (angle) allowed during lofting operation in order to smooth it.

Parameters:

ohSmoothAngleThresholdCkeParm: Length literal feature.

o GetSmoothAngleThresholdActivity

public virtual GetSmoothAngleThresholdActivity( isSmoothAngleThresholdActivity)

Gets information whether a angular threshold is allowed or not during lofting operation in order to smooth it.

Parameters:

isSmoothAngleThresholdActivity: TRUE or FALSE (FALSE if not specified).

o GetSmoothDeviation

public virtual GetSmoothDeviation( oSmoothDeviation)

Gets deviation value (length) allowed during lofting operation in order to smooth it.

Parameters:

oSmoothDeviation: Numerical value.

o GetSmoothDeviation

public virtual GetSmoothDeviation( ohSmoothDeviationCkeParm)

Gets deviation value (length) allowed during lofting operation in order to smooth it.

Parameters:

ohSmoothDeviationCkeParm: Length literal feature.

o GetSmoothDeviationActivity

public virtual GetSmoothDeviationActivity( isSmoothDeviationActivity)

Gets information whether a deviation is allowed or not during lofting operation in order to smooth it.

Parameters:

isSmoothDeviationActivity: TRUE or FALSE (FALSE if not specified).

o GetSpine

public virtual GetSpine(		`oSpineType`,
		`oSpine`)

Gets the spine of the lofted surface.

Parameters:

oSpineType: type of spine.

See also:

oSpine

curve used as a spine, if iSpineType = CATGSMLoftUserSpine

o ModifyGuideCurve

public virtual ModifyGuideCurve(	const	`iGuide`,
	const	`iNewGuide`)

Modifies the curve of a guide from the lofted surface.

Parameters:

iGuide: guide curve to be replaced.
iNewGuide: guide curve, will replace iGuide.

o ModifySectionCurve

public virtual ModifySectionCurve(	const	`iSection`,
	const	`iNewSection`)

Modifies the curve of section from the lofted surface.

Parameters:

iSection: section curve to be replaced.
iNewSection: section curve, will replace iSection.

o ModifySectionCurve

public virtual ModifySectionCurve(	const	`iSection`,
	const	`iNewSection`,
		`oCurveSection`,
		`oClosingPoint`,
		`oPtDiag`)

Modifies the curve of section from the lofted surface.

Parameters:

iSection: section curve to be replaced.
iNewSection: section will replace iSection, can be a curve or a face
oCurveSection: if iSection is a face, oCurveSection is the boundary of the face. oCurveSection is used as section curve. if Part design, the face is used to close the Loft.
oClosingPoint: if iSection is a closed curve, oClosingPoint is a new closing point of iSection. if iSection is a face, oClosingPoint is a new closing point the boundary of iSection.

o ModifySectionOrient

public virtual ModifySectionOrient(	const	`iSection`,
		`iOrient`	`= CATGSMSameOrientation` )

Modifies the orientation of the curve of a section from the lofted surface.

Parameters:

iSection: section curve to be replaced.
iOrient: orientation of the section curve :

See also:

o RemoveFaceForClosing

public virtual RemoveFaceForClosing( const iSection)

Removes face used to close the lofted surface.

Parameters:

iSection: section curve.

o RemoveGuide

public virtual RemoveGuide( const iGuide)

Removes guide from the lofted surface.

Parameters:

iGuide: guide curve to be removed, if this guide has a support surface it will be removed too.

o RemoveGuideSupport

public virtual RemoveGuideSupport( const iGuide)

Removes a support surface of a guide from the lofted surface.

Parameters:

iGuide: Guide curve of the loft to which the surface will be removed.
iContinuity: Continuity between the support and the loft (accepted values are CATGSMContinuity_Tangency or CATGSMContinuity_Curvature).

o RemoveGuideTangent

public virtual RemoveGuideTangent( const iGuide)

Deprecated:

V6R2013x CATIGSMUseLoft#RemoveGuideSupport Removes a support surface of a guide from the lofted surface.

Parameters:

iGuide: guide curve of the guide to which the surface will be removed.

o RemoveSection

public virtual RemoveSection( const iSection)

Removes section from the lofted surface.

Parameters:

iSection: section curve to be removed, if this section has a closing point it will be removed too.

o RemoveSectionPoint

public virtual RemoveSectionPoint( const iSection)

Removes a closing point of a section from the lofted surface. The curve section must be closed curve.

Parameters:

iSection: section curve of the section to which the point will be removed.

o RemoveSectionSupport

public virtual RemoveSectionSupport( const iSection)

Removes a support surface of a section from the lofted surface.

Parameters:

iSection: Section curve of the loft to which the surface will be removed.
iContinuity: Continuity between the support and the loft (accepted values are CATGSMContinuity_Tangency or CATGSMContinuity_Curvature).

o RemoveSectionTangent

public virtual RemoveSectionTangent( const iSection)

Deprecated:

V6R2013x CATIGSMUseLoft#RemoveSectionSupport Removes the support surface of a section from the lofted surface. The section must be the start section or the end section of the loft.

Parameters:

iSection: section curve of the section to which the support will be removed.

o SetAreaLaw

public virtual SetAreaLaw( const iLaw)

Sets the optional area law for multi-sections element definition. The input law must be a length law: the applied area law is the square of the input law multiplied by PI. Use NULL_var input to remove the law.

Parameters:

iLaw: Input length law for area definition

See also:

o SetAreaLawTolerance

public virtual SetAreaLawTolerance( iLawTolerance)

Sets the tolerance applied to area law, if specified. As area law is specified through a length law, tolerance is also a length.

Parameters:

iLaw: Input area law tolerance value in mm

See also:

o SetBooleanOperation

public virtual SetBooleanOperation( const iOperation = CATGSMLoftBooleanUnion )

Sets boolean operation for closed lofted surface. TO BE USED ONLY for Part Loft (closed loft)

Parameters:

iOperation: type of operation.

See also:

o SetCanonicalDetection

public virtual SetCanonicalDetection( const iDetection = CATGSMCanonicalDetection)

Sets information about detection of canonical surfaces of the output surface.

Parameters:

iDetection: if canonical surfaces are detected and converted into plane or not and how; possible values are CATGSMNoDetection, CATGSMPlaneOnlyDetection and CATGSMCanonicalDetection.

See also:

o SetCompSectionTangent

public virtual SetCompSectionTangent(	const	`iSection`,
	const	`iCompSectionTangent`)

Sets a computed tangent surface to the start section or end section. from the lofted surface. The section must have been set as a face.

Parameters:

iSection: section curve of the section to which the tangent will be computed.
iCompSectionTangent: section tangent is computed or not,

See also:

o SetContext

public virtual SetContext( const iContextType)

Sets context type to generate a Surface or Volume.

Parameters:

iContextType: CATGSMSurfaceCtxt to generate a surface, CATGSMVolumeCtxt (requires GSO License) to generate a volume

See also:

o SetFaceForClosing

public virtual SetFaceForClosing(	const	`iSection`,
	const	`iFace`)

Sets face for closing the lofted surface.

Parameters:

iSection: section curve.
iFace: End face used to close the loft.

o SetGuideSupport

public virtual SetGuideSupport(	const	`iGuide`,
	const	`iSupportGuide`,
	const	`iContinuity`)

Sets a support surface to a guide from the lofted surface.

Parameters:

iGuide: Guide curve of the loft to which the support will be added.
iSupportGuide: Support surface to be added, the curve must be layed on the surface.
iContinuity: Continuity between the support and the loft (accepted values are CATGSMContinuity_Tangency or CATGSMContinuity_Curvature).

o SetGuideTangent

public virtual SetGuideTangent(	const	`iGuide`,
	const	`iSupportGuide`)

Deprecated:

V6R2013x CATIGSMUseLoft#SetGuideSupport Sets a support surface to a guide from the lofted surface.

Parameters:

iGuide: guide curve of the guide to which the support will be added
iSupportGuide: support surface to be added, the curve must be layed on the surface.

o SetRelimitation

public virtual SetRelimitation( const iRelimitation = CATGSMLoftRelimitOnLimitSections )

Sets informations about relimitation of the lofted surface.

Parameters:

iRelimitation: type of relimitation.

See also:

o SetSectionCoupling

public virtual SetSectionCoupling( const iCoupling = CATGSMRatioCoupling )

Sets informations about the coupling between section of the lofted surface.

Parameters:

iCoupling: type of coupling between section.

See also:

o SetSectionPoint

public virtual SetSectionPoint(	const	`iSection`,
	const	`iPointSection`)

Sets a closing point to a section from the lofted surface. The curve section must be closed curve.

Parameters:

iSection: section curve of the section to which the point will be added.
iPointSection: point to be added

o SetSectionSupport

public virtual SetSectionSupport(	const	`iSection`,
	const	`iSupportSection`,
	const	`iContinuity`)

Sets a support surface to a section from the lofted surface.

Parameters:

iSections: Section curve of the loft to which the support will be added.
iSupportSection: Support surface to be added, the curve must be layed on the surface.
iContinuity: Continuity between the support and the loft (accepted values are CATGSMContinuity_Tangency or CATGSMContinuity_Curvature).

o SetSectionTangent

public virtual SetSectionTangent(	const	`iSection`,
	const	`iSupportSection`)

Deprecated:

V6R2013x CATIGSMUseLoft#SetSectionSupport Sets a support surface to a section from the lofted surface. The section must be the start section or the end section of the loft.

Parameters:

iSection: section curve of the section to which the support will be added
iSupportSection: support surface to be added, the curve must be layed on the surface.

o SetSmoothAngleThreshold

public virtual SetSmoothAngleThreshold( const iSmoothAngleThreshold)

Sets angular threshold value (angle) allowed during lofting operation in order to smooth it.

Parameters:

iSmoothAngleThreshold: Numerical value.

o SetSmoothAngleThreshold

public virtual SetSmoothAngleThreshold( const ihSmoothAngleThresholdCkeParm)

Sets angular threshold value (angle) allowed during lofting operation in order to smooth it.

Parameters:

ohSmoothAngleThresholdCkeParm: Length literal feature.

o SetSmoothAngleThresholdActivity

public virtual SetSmoothAngleThresholdActivity( const isSmoothAngleThresholdActivity)

Sets information whether a angular threshold is allowed or not during lofting operation in order to smooth it.

Parameters:

isSmoothAngleThresholdActivity: TRUE or FALSE (FALSE if not specified).

o SetSmoothDeviation

public virtual SetSmoothDeviation( const iSmoothDeviation)

Sets deviation value (length) allowed during lofting operation in order to smooth it.

Parameters:

iSmoothDeviation: Numerical value.

o SetSmoothDeviation

public virtual SetSmoothDeviation( const ihSmoothDeviationCkeParm)

Sets deviation value (length) allowed during lofting operation in order to smooth it.

Parameters:

ihSmoothDeviationCkeParm: Length literal feature.

o SetSmoothDeviationActivity

public virtual SetSmoothDeviationActivity( const isSmoothDeviationActivity)

Sets information whether a deviation is allowed or not during lofting operation in order to smooth it.

Parameters:

isSmoothDeviationActivity: TRUE or FALSE.

o SetSpine

public virtual SetSpine(	const	`iSpineType`	`= CATGSMLoftCalculatedSpine` ,
	const	`iSpine`	`= NULL_var` )

Sets the spine to the lofted surface.

Parameters:

iSpineType: type of spine.

See also:

iSpine

curve to be added as a spine, if iSpineType = CATGSMLoftUserSpine

This object is included in the file: CATIGSMUseLoft.h
If needed, your Imakefile.mk should include the module: CATGSMUseItf